By default, these options are not selected.
Keep product properties
This applies to the Product tab of the properties for both parts and
products.
Example: This is what appears in the Product tab before filtering:
If you do not select Keep product properties, all information is lost:
 |
If you select the Keep product properties, you
will transfer the product information.
Only the Part Number will
change:
 |
Keep colors and attributes on subelements
This option overrides the standard behavior for colors and attributes and
keeps the visual aspect of the original data.
For example, the color of one face has been changed:
If you do not select Keep colors and attributes on subelements,
the whole solid takes the color of the original body, as explained
in the standard behavior.
If you select Keep colors and attributes on subelements, the
color you have applied to the face is kept:
- Be aware that this option may be time consuming.
- If a Body is not up-to-date (update icon displayed in the tree), the color of the subelements will not be kept even if this option is selected.
- When the color or the opacity of a subelement has been overloaded (at the level of the subelement or at the level of one of its parents), in the result part, the overloaded color or opacity is kept on the subelement, but can be changed at the level of the subelement only, not at that of its parents. If you overload the color or opacity of one of its parents, the color or opacity of the subelement will not change.
Keep 2D Layout for 3D Design data
2D Layout for 3D Design data can be processed only if they can be visualized in the 3D Viewer. 2D Layout for 3D Design data that are in No-show in the origin documents are transferred and are in No-show in the filtered documents.
In the case of a global transfer (all options are selected), 2D Layout for 3D Design data will be reconnected to the elements that were pointed, with the exception of 2D profiles generated from 2D geometry of 2D Layout for 3D Design views that are no longer linked to filtered geometry. In particular, 2D Layout for 3D Design filters will be transferred and filtered objects will be correctly managed in destination document. No difference will be visible on resulting 2D Layout for 3D Design visualization.
In the case of a partial transfer (some options are not selected), 2D Layout for 3D Design data will be totally transferred, but some 2D Layout for 3D Design objects will point to non transferred objects (e.g. non transferred annotations cannot be pointed by transferred 2D layout filters).
All objects (sheets, views, 2D component references and 2D component instances, 2D geometries, annotations, layout filters etc) will be transferred and visible but in some cases objects will be isolated (e.g. annotations that cannot be rerouted on a translated object). Non translated objects will be removed from transferred filters.
As 3D data and 2D data are transferred in separate steps, profiles in 3D generated from 2D geometry in 2D Layout for 3D Design will be isolated from their 2D geometry in 2D layout after filtering.
All texts are isolated (no more attribute links). In particular, texts under views with scale factor will lose that scale factor.
Links to the catalog of details are kept after filtering. This means that if the catalog is in the input CATPart, the result CATPart will have a link with the input CATPart
- To prevent the creation of a document with corrupted data, when part of the 2D Layout for 3D Design data cannot be transferred correctly, an error occurs and no document is created.
- When this option is selected, the input CATPart is modified, but not the data it contains. You need not save the input CATPart.
- The update status of 2D Layout objects (layout, sheet, view) may change is some cases. For example, if a view is associated to a 3D plane, the corresponding view in the output document will not be up-to-date as the association has been re-created with new 3D plane.
- Curvilinear dimensions with Offset or Parallel representation modes do not support isolated state. As a consequence, rather than turning to isolated analysis display color, they turn to not-up-to- date analysis color.
Keep annotations
Annotations can be processed only if they are visualized in the 3D
Viewer.
Select this option to transfer annotations.
You will find below explanations on what happens.
Non-displayed 3D Functional Tolerancing & Annotation Features
When Keep annotations is selected, the 3D Functional Tolerancing & Annotation data are all transferred even if they are not displayed:
- The 3D Functional Tolerancing & Annotation features that are in No-show in the origin documents are transferred and are in No-show in the filtered documents.
- The 3D Functional Tolerancing & Annotation features that are in a given layer in the origin documents will be in the same the same layer in the filtered documents even if the Keep layers and filters definition option is not selected.
- The 3D Functional Tolerancing & Annotation features are transferred
even if the filters applied to the origin documents make them not
displayed:
- If the Keep layers and filters definition option is selected, the display of the 3D Functional Tolerancing & Annotation features in the filtered documents is exactly the same as the display of the 3D Functional Tolerancing & Annotation features in the origin documents.
- If the Keep layers and filters definition option is not selected, all the 3D Functional Tolerancing & Annotation features (that are in show mode) of the filtered documents are visible.
- Even if the annotation sets are switched off in the origin documents, the 3D Functional Tolerancing & Annotation data are transferred (see Disabling/Enabling Annotations in the 3D Functional Tolerancing & Annotation user's guide). The transferred annotation sets are in the same state (switched on or switched off) in the filtered documents than in the origin documents.
Names of the Transferred 3D Functional Tolerancing & Annotation Features
The transferred 3D Functional Tolerancing & Annotation features are
displayed in the feature tree with the same names as in the origin documents
and in the exact same order.
The names of the Geometrical Links features of the transferred 3D
Functional Tolerancing & Annotation features
are partially kept:
- The names of Group Of Surfaces and User Surface features are kept.
- The names of Geometric Component features are not kept. They are getting a default name in the filtered documents.
Old Construction Geometry Features
The old construction geometry features (created before V5R13 and
displayed under an OpenBody for 3D Annotations node) are special
GSD features.
These features are not fully transferred. They are transferred as datums as
any other GSD feature but are no longer editable in the filtered documents.
All the 3D Functional Tolerancing & Annotation features that are applied to
them in the origin documents are transferred and applied to the
corresponding datum geometry in the filtered documents.
New Construction Geometry Features
The new construction geometry features (displayed under the Construction geometries node of the Annotation Set in the feature tree) are fully transferred and can be edited in the filtered documents.
Thread Construction Geometry
Thread construction geometry features are linked to Part Design threaded
hole features or thread features or their corresponding Technological Result
thread features.
The threaded hole features or thread features are not transferred but the
corresponding Technological Result thread features are.
Case of old construction geometry (see above)
The transferred thread construction geometry features are invalid and all the annotations that are linked to them are invalid.
Case of new construction geometry (see above)
If the Technological Result thread features have not been generated, the transferred thread construction geometry features are invalid and all the annotations that are linked to them are invalid.
If the Technological Result thread features have been generated, the
transferred thread construction geometry features are valid.
They are linked to the Technological Result thread features (even if they
were linked to the threaded hole feature or the thread feature).
All the annotations that are linked to them are valid too.
Note that:
- Technological Result thread features can be generated on Part Design threaded hole features or thread features, whatever their creation level.
- The described behavior will work for any new thread construction geometry features whatever their creation level.
Parameters Linked to 3D Functional Tolerancing & Annotation Features
All the parameters of the 3D Functional Tolerancing & Annotation features
are transferred.
All the formulas on these parameters are not transferred but the value of
the 3D Functional Tolerancing & Annotation parameters are kept.
The attributes links of 3D Functional Tolerancing & Annotation text features
are not transferred but the content of the text is fully kept.
3D Functional Tolerancing & Annotation parameters of origin
document: 
3D Functional Tolerancing & Annotation parameters of filtered
document:
The links to Generative Parameters are not kept.
Tabulated geometrical tolerances that are based on the existence of length parameters having the names of the tabulated tolerances displayed in the callout are transferred but are invalid in the filtered documents because the corresponding length parameters are not transferred.
3D Functional Tolerancing & Annotation Captures
The result on screen of the display of a transferred capture is the same as the result on screen of the display of the origin capture, except for the following cases:
- The geometry of the geometrical sets or bodies the capture is displaying has not been transferred (this is the case when the geometry is in no-show in the origin documents).
- The filtered 3D Functional Tolerancing & Annotation features are invalid while the corresponding origin features are valid (the invalid filtered 3D Functional Tolerancing & Annotation features are displayed in the color that corresponds to the invalid 3D Functional Tolerancing & Annotation features.
3D Functional Tolerancing & Annotation Captures Linked to Cameras
All the cameras that are linked to 3D Functional Tolerancing & Annotation captures are partially transferred:
- The camera feature itself is not transferred.
- The view point definition of the camera is transferred as 3D Functional Tolerancing & Annotation capture feature view point attributes.
- When editing the capture in the filtered document, UndefCam is displayed in the Capture Options panel to let you know that a view point is defined but is not linked to any camera feature.
- When editing a capture that uses a Camera in the origin document, the
name of the used camera is displayed in the Capture Options panel.
When editing the corresponding transferred Capture in the filtered document, UndefCam is displayed in the Capture Options panel.
Note Object Attribute From a Ditto
Instances of Note Object Attribute From a Ditto are transferred by removing the link (if any) to the document that contains the reference Note Object Attribute. The instances of Note Object Attribute From a Ditto in the filtered documents are linked to the CATDrawing documents that contain the corresponding detail.
Behavior of 3D Functional Tolerancing & Annotation Features that cannot be rerouted on the Datum Geometry of the Filtered Documents
When there is no datum geometry that corresponds to the origin geometry (e.g. when the geometry in the original documents is in no-show – except for the XY, YZ, ZX planes that always exist in the result products), the 3D Functional Tolerancing & Annotation features behave as follows:
- Annotation features: The annotations features are transferred but are
invalid.
Even if they are invalid, they are displayed exactly as the original features (same position, same values …) except for the color that corresponds to the 3D Functional Tolerancing & Annotation invalid features color (dark brown by default).
Original Part:
Filtered part:
- Construction Geometry features:
The Construction Geometry features are transferred but are invalid. - Restricted area features:
The Restricted area features are transferred but are invalid. - Views (that are associative to the geometry):
The views are transferred but are no longer associative with the geometry.
3D Functional Tolerancing & Annotation Features Belonging to Selection Sets
If the option Keep selection sets is selected, the 3D Functional Tolerancing & Annotation features belonging to selection sets will be kept in the selection sets of the transferred documents.
- when 3D Functional Tolerancing & Annotation features cannot be transferred correctly, an error occurs and no filtered CATPart is created.
- 3D Functional Tolerancing & Annotation features defined at product level are not kept when performing a product to product filtering.
- V4 Functional Dimensioning and Tolerancing data are not kept when performing a product to product filtering.
- The graphic properties of element in the sketch used for extraction are not kept.
- Sketches defining extraction views (Offset Section view and Aligned
Section view) are not transferred as plain datums.
The result is a sketch with elementary features (points, lines, curves). - When you filter CATParts that contain 3D Functional Tolerancing & Annotation features with the option Keep annotation selected, you are asked to save the origin CATPart when you close it. Do not save the origin CATPart, unless you have modified it.
Keep publications
Select this option to transfer publications.
Keep selection sets
Select this option to transfer selection sets.
Keep layers and filters definition
Select this option to transfer layers definition (layer name and definition) and filters definition (filter name and definition).
More information
- Filtering applies only to the contents of Bodies, Geometrical Sets or Ordered Geometrical Sets.
- When an Ordered Geometrical Set is filtered, solids are transferred first, then the surfacic entities are transferred. In the resulting CATPart, you will find the solids at the beginning of the list of the entities of the Ordered Geometrical Set, even though there were surfacic entities before those solids in the input CATPart.
- The change of an In Work Object is not taken into account. The geometry is transferred in its final status, not in the intermediate one.
- Only visible geometries are transferred. In some cases, no empty
bodies are created in the resulting CATPart, with the following exception:
- Since a CATPart is always created with a PartBody, you will always find one in the result CATPart.
- If there was a non-empty PartBody in the original CATPart, the result CATPart will contain two nodes PartBody, one empty created when the result CATPart was created, one containing the geometry from the PartBody of the original CATPart, which is a Body with the same name as the PartBody of the original CATPart.
- The option Checking Operation When Renaming: Under the same tree node in Tools > Options > Infrastructure > Part Infrastructure > Display, is inefficient in Product Data Filtering. Therefore be aware that you can find several elements with the same name under one node.
- If a publication, selection set or a layer refers to a geometry placed in the NoShow in the original CATPart, this publication, selection set or a layer is not transferred.
- When annotations are transferred, the active view of the resulting CATPart is not necessarily that of the input CATPart.
- Elements other than the geometry and the axis system or those processed by the options above are never transferred.