Create a Hanger 

This task shows you how to create a hanger.  
Before you create parts you should specify where they will be stored. A default directory is specified but if you change it see Understanding Project Resource Management. The parts are normally moved from this directory into the catalog. You should also create a graphic representations file and specify where it is located. (See Defining Directory Paths and Define Graphic Representations for a Part.)

See also Definition of Hanger Attributes.

If you want to be able to use the same hanger in other V5 applications, such as Electrical Harness Discipline applications, as well as other Equipment and Systems applications such as Piping and Tubing, then it is recommended you do the following. It is important that you perform them in the order described below.

  • Create the hanger using the build process described in this task. Assigning a type to the hanger first, using the Hanger Design workbench, will allow you to use it in other disciplines.
  • Add connectors as described in Creating Connectors.
  • Add electrical harness features such as type and entry/exit planes.
  • Add the part to the Hanger Design catalog. You will now be able to use the same hanger for Electrical Harness Discipline applications also. You can also add the hanger to Electrical Harness Discipline catalogs.

1.

 Click the Build Hanger Part button . The Create Part dialog box appears.

 

2. Click the Display Class Browser button next to the Component Type field. The Class Browser displays.

3. The Class Browser allows you to select the type of hanger you want to create. Navigate to the type you want by clicking on the "plus" sign next to each directory, or by using the three navigation buttons at the bottom. You can also filter for certain types. For instance, you can enter "rack" in the Filter field and hit enter to see all rack types. Click OK after making your selection. After you click OK the Class Browser will close and the part you selected will display in the Component Type field of the Create Part dialog box.
4. The File Open button is used to bring up a part, say, if you did not finish creating it and had to close the application. Using the File Open button you can navigate to the directory where the part is stored.
5. The Define Properties button brings up the Properties box, allowing you to change properties if needed.

If you are building a hanger that is to be placed on a run you must define the Standard attribute.
6. The Override Parameters button button brings up a dialog box which allows you to override a parameter. When you click on a parameter on the left side of the box and then click on the arrow to bring it on the right side, that means the parameter can be overridden. (See Change the Parameters of a Part.) When you place this part the application will try to determine a value for that parameter. If it cannot, then you will be asked to enter one.

7. Click the Design Table button to create a design table and associate it to the part you are creating. For more information on this see the Infrastructure document - Advanced Tasks - Using Knowledgeware Capabilities.
8. Click the Formula button to create formulas and parameters. See the Knowledgeware document mentioned above for more information.
9. The Define Connectors button allows you to add connectors.
10. The Associate Attributes to Connectors button lets you associate specifications to connectors.
11. The Manage Representation button lets you create and manage graphic representations.
  12. The Set Object Type button can be used to set the object type.
13. Click the Use ID Schema button next to the File Name field if you want the application to generate a name for the part.
14. Enter a name for the part in the Symbol Name field and press Enter. Click Apply or OK. The part is created. In the illustration below it has been named Rack2.

The part has been created but it still does not have a graphic representation - it has no "looks". You will learn how to create one or more graphic representations for the part in subsequent tasks.
15. You must save the part to the directory specified in your Options dialog box. Double-click on the part Rack2 (in the image above) to make it active, and then use the File menu to save it.