Indexes

HybridShapeLoft (Object)

Represents the hybrid shape loft surface feature object.
Role: To access the data of the hybrid shape loft surface feature object.
This data includes:

The spine
The tangent surfaces to the start and end sections
Guide curves, sections, and couplings

Use the CATIAHybridShapeFactory to create a HybridShapeLoft object.

LICENSING INFORMATION: Creation of volume result requires GSO License
if GSO License is not granted , settting of Volume context has not effect

Use the CATIAHybridShapeFactory to create a HybridShapeLoft object.

See also:: HybridShapeFactory

BooleanOperation: Gets or sets the boolean operation for closed lofted surface.
CanonicalDetection: Returns or sets whether canonical surfaces of the lofted surface are detected.
CompEndSectionTangent: Returns or sets whether the tangent surface to the end section of the lofted surface is computed.
CompStartSectionTangent: Returns or sets whether the tangent surface to the start section of the lofted surface is computed.
Context: Returns or sets the context on Loft feature.
Relimitation: Returns or sets the relimitation type between sections of the loft.
SectionCoupling: Returns or sets the type of coupling between sections of the loft.
SmoothAngleThresholdActivity: Returns or sets whether a angular threshold is allowed or not during lofting operation in order to smooth it.
SmoothAngleThreshold: Returns or sets the angular threshold under which discontinuities (moving frame, tangency net on reference surface) will be smoothed.
SmoothDeviationActivity: Returns or sets whether a deviation is allowed or not during lofting operation in order to smooth it.
SmoothDeviation: Returns or sets the deviation value (length) allowed during lofting operation in order to smooth it.

AddGuideWithTangent: Adds a guide curve and a tangent surface to the lofted surface.
AddGuide: Adds a guide curve to the lofted surface.
AddSectionToLoft: Retrieves a loft section.
GetFacesForClosing: Gets start and end faces if the tangent is a computed tangent surface to the start section or end section, from the lofted surface.
GetGuide: Gets informations about the guide at a specified position in the list of the lofted surface.
GetNbOfGuides: Returns the number of guides in the loft object.
GetSectionFromLoft: Retrieves a loft section information.
GetSpine: Gets the spine of the lofted surface.
GetStartAndEndSectionTangent: Gets the start and end section tangents of the lofted surface.
InsertCouplingPoint: Inserts a coupling point to a coupling of the lofted surface.
InsertCoupling: Inserts a coupling to the loft.
InsertSectionToLoft: Inserts a loft section.
ModifyGuideCurve: Modifies the curve of a guide from the lofted surface.
ModifySectionCurve: Modifies the curve of section from the lofted surface.
ModifySectionOrient: Modifies the orientation of the curve of a section from the lofted surface.
RemoveFaceForClosing: Removes face used to close the lofted surface.
RemoveGuideTangent: Removes a tangent surface of a guide from the lofted surface.
RemoveGuide: Removes a guide curve from the lofted surface.
RemoveSectionPoint: Removes a closing point of a section from the lofted surface.
RemoveSectionTangent: Removes the tangent surface of a section from the lofted surface.
RemoveSection: Removes a loft section from the lofted surface.
SetEndFaceForClosing: Sets a face to the end section from the lofted surface.
SetEndSectionTangent: Sets a tangent surface to the end section from the lofted surface.
SetSpine: Sets the spine to the lofted surface.
SetStartFaceForClosing: Sets a face to the start section from the lofted surface.
SetStartSectionTangent: Sets a tangent surface to the start section from the lofted surface.

Properties

o Property BooleanOperation(

) As

Gets or sets the boolean operation for closed lofted surface. TO BE USED ONLY for Part Loft (closed loft). BooleanOperation = 1 : No boolean operation. = 2 : Union boolean operation. = 3 : Removal boolean operation. This example retrieves in BoolOp the type of boolean operation for the Loft hybrid shape feature.

 Dim BoolOp
 BoolOp = Loft.BooleanOperation

o Property CanonicalDetection(

) As

Returns or sets whether canonical surfaces of the lofted surface are detected.
Legal values:

0: No detection of canonical surface is performed
1: Detection of planar surfaces only is performed
2: Detection of canonical surfaces is performed

o Property CompEndSectionTangent(

) As

Returns or sets whether the tangent surface to the end section of the lofted surface is computed.
Legal values:

1: The tangent to the end section is computed
2: The tangent to the end section is not computed

o Property CompStartSectionTangent(

) As

Returns or sets whether the tangent surface to the start section of the lofted surface is computed.
Legal values:

1: The tangent to the start section is computed
2: The tangent to the start section is not computed

o Property Context(

) As

Returns or sets the context on Loft feature.
Legal values:

0 This option creates Lofted surface.
1 This option creates Lofted volume.

Note: Setting volume result requires GSO License.

Example:

This example retrieves in oContext the context for the Loft hybrid shape feature.

 Dim oContext
 Set oContext = Loft.Context

o Property Relimitation(

) As

Returns or sets the relimitation type between sections of the loft.
NOT YET IMPLEMENTED.
Legal values:

1

The loft will be swept along the spine, then relimited by the start section and the end section

2

The loft will be swept along the spine.

If the spine is a user spine, then the loft is limited by the spine extremities
If the spine is a computed spine, then the loft is limited:
- By the start section and the end section, if there is no guide
- By the guides extremities, if there are guides

3

The loft will be swept along the spine, then relimited by the first section,

If the spine is a user spine, then the loft is limited by the spine extremity opposite to the first section
If the spine is a computed spine, then the loft is limited:
- By the last section, if there is no guide
- By the guides extremities opposite to the first section, if there are guides

4

The loft will be swept along the spine, then relimited by the last section,

If the spine is a user spine, then the loft is limited by the spine extremity opposite to the last section
If the spine is a computed spine, then the loft is limited:
- By the first section, if there is no guide
- By the guides extremities opposite to the last section, if there are guides

o Property SectionCoupling(

) As

Returns or sets the type of coupling between sections of the loft.
Legal values:

1: The curves will be coupled according to the curvilinear abscissa ratio
2: if each curve has the same number of tangency discontinuity points, then these points will be coupled, otherwise an error message is displayed
3: if each curve has the same number of tangency and curvature discontinuity points, then tangency discontinuity points will be coupled, and after curvature discontinuity points will be coupled, otherwise an error message is displayed
4: if each curve has the same number of vertices, then these points will be coupled, otherwise an error message is displayed

o Property SmoothAngleThresholdActivity(

) As

Returns or sets whether a angular threshold is allowed or not during lofting operation in order to smooth it.
Legal values:

TRUE: The angular threshold value is used during the lofting operation
FALSE: The angular threshold value is not used during the lofting operation

o Property SmoothAngleThreshold(

) As

Returns or sets the angular threshold under which discontinuities (moving frame, tangency net on reference surface) will be smoothed.

o Property SmoothDeviationActivity(

) As

Returns or sets whether a deviation is allowed or not during lofting operation in order to smooth it.
Legal values:

TRUE: The deviation value is used during the lofting operation
FALSE: The deviation value is not used during the lofting operation

o Property SmoothDeviation(

) As

Returns or sets the deviation value (length) allowed during lofting operation in order to smooth it.

Methods

o Sub AddGuideWithTangent(		`iGuide`,
		`iTangent`)

Adds a guide curve and a tangent surface to the lofted surface.

Parameters:

o Sub AddGuide( iGuide)

Adds a guide curve to the lofted surface.

Parameters:

o Sub AddSectionToLoft(		`iCrv`,
		`iOri`,
		`iPoint`)

Retrieves a loft section.

Parameters:

iCrv: Reference to the curve
iOri: Orientation
iPoint: Reference to the Closing Point

o Sub GetFacesForClosing(		`oStartFace`,
		`oEndFace`)

Gets start and end faces if the tangent is a computed tangent surface to the start section or end section, from the lofted surface. The section must have been set as a face.

Parameters:

oStartFace: start face used to close the loft.
oEndFace: end face used to close the loft.

o Sub GetGuide(		`iPos`,
		`oGuide`,
		`oGuideTangent`)

Gets informations about the guide at a specified position in the list of the lofted surface.

Parameters:

iPos: position of the guide in the list where the information is retrieved.
oGuide: the guide curve.
oGuideTangent: the tangent corresponding to the guide curve.

o Func GetNbOfGuides(

) As

Returns the number of guides in the loft object.

Parameters:

oSize

Number of guides in the loft.

Example:

This example retrieves the number of guides in the hybShpLoft hybrid shape Loft.

 Dim oSize As  long
 oSize = hybShpLoft.GetNbOfGuides

o Sub GetSectionFromLoft(		`iRank`,
		`oCrv`,
		`oOri`,
		`oPoint`)

Retrieves a loft section information.

Parameters:

iRank: The index of the section
oCrv: The reference to the curve
oOri: The orientation value
oPoint: The reference to the point

o Sub GetSpine(		`oSpineType`,
		`oSpine`)

Gets the spine of the lofted surface.

Parameters:

oSpineType: type of spine = 1 : User defined spine. = 2 : Automatically computed spine.
oSpine: curve used as a spine, if the spine is user defined one.

o Sub GetStartAndEndSectionTangent(		`oStartSectionTangent`,
		`oEndSectionTangent`)

Gets the start and end section tangents of the lofted surface.

Parameters:

oStartSectionTangent: tangent surface at start section.
oEndSectionTangent: tangent surface at end section.

o Sub InsertCouplingPoint(		`iCouplingIndex`,
		`iPosition`,
		`iPoint`)

Inserts a coupling point to a coupling of the lofted surface.

Parameters:

o Sub InsertCoupling( iPosition)

Inserts a coupling to the loft.

Parameters:

o Sub InsertSectionToLoft(		`iType`,
		`iCrv`,
		`iOri`,
		`iPoint`,
		`iSectionRef`)

Inserts a loft section.

Parameters:

iType: iType if set to true section is added After and iType if set to false section is added Before iSectionRef
iCrv: Reference to the curve
iOri: Orientation
iPoint: Reference to the Closing Point
iSectionRef: iSectionRef is the section before and after which section is added.

o Sub ModifyGuideCurve(		`iGuide`,
		`iNewGuide`)

Modifies the curve of a guide from the lofted surface.

Parameters:

iGuide: guide curve to be replaced.
iNewGuide: new guide curve, will replace iGuide.

o Sub ModifySectionCurve(		`iSection`,
		`iNewSection`,
		`oCurveSection`,
		`oClosingPoint`,
		`oPtDiag`)

Modifies the curve of section from the lofted surface.

Parameters:

iSection: section curve to be replaced.
iNewSection: section will replace iSection, can be a curve or a face
oCurveSection: if iSection is a face, oCurveSection is the boundary of the face. oCurveSection is used as section curve. if Part design, the face is used to close the Loft.
oClosingPoint: if iSection is a closed curve, oClosingPoint is a new closing point of iSection. if iSection is a face, oClosingPoint is a new closing point the boundary of iSection.
oPtDiag: Information on closing point = 0 : No closing point has been created nor retrieved. = 1 : A closing point has been created as a vertex. = 2 : A closing point has been created as an extremum. = 3 : A closing point has been retrieved as an extremum.

o Sub ModifySectionOrient(		`iSection`,
		`iOrient`)

Modifies the orientation of the curve of a section from the lofted surface.

Parameters:

iSection: section curve to be modified.
iOrient: orientation of the section curve = 1 : same orientation. = -1 : inverted orientation. = 2 : ko orientation.

o Sub RemoveFaceForClosing( iSection)

Removes face used to close the lofted surface.

Parameters: