Creating a 3D Plane  

This task shows you how to create a 3D plane.

Open the Disk3.CATPart document. Select Start > Mechanical Design > 2D Layout for 3D Design to open the layout in the 2D window.

  1. Double-click the front view to activate it.

  2. Click 3D Plane in the 3D Geometry toolbar (3D Outputs sub-toolbar).
     

                                                                   

    The Tools Palette appears.

  3. Enter a name for your 3D plane in the Tools Palette.

    • If you select only one plane, the plane is named as entered in the Tools Palette.
    • If you select more than one plane, then the planes are named as XXX.1, XXX.2, etc., where XXX is the name entered.
    • If no name is given the planes are created with default naming Plane2DL.X.
    • If you right-click an element and select 3D Plane command (i.e. you follow the object/action mode), the Tools Palette is not available.

  4. Select the line in the section view as shown below.
     

    The 3D plane, Plane2DL.1, is created and it is listed in the specification tree, under the PartBody node.

     

    • Of all elements created from 2D geometry in 2D Layout for 3D Design, only 3D profiles and 3D planes belong to the current part body.
    • Note that 3D profiles and 3D planes are created under the current part body only when working in a hybrid design environment, that is when the Enable hybrid design inside part bodies and bodies option is selected in Tools > Options > Infrastructure > Part Infrastructure > Part Document tab (which is the case by default). Otherwise, when this option is not selected, 3D profiles and 3D planes are created in geometrical sets or ordered geometrical sets.

    The 3D plane is also displayed in the 3D window.

     
  5. (Optional) Select one or several other lines.
    Several 3D planes are created in one shot.